Skip to content
Formulaxis

Machining and manufacturing

Milling feed: calculate table feed and feed per tooth

Relate table feed, feed per tooth, spindle speed and the number of active teeth of a milling cutter. Choose the quantity to find; the calculated number of teeth remains a theoretical value to compare with an actual tool.

Created on , Revised on v2.0

Method and validation

Milling feed and chip load per tooth

Linear displacement in the feed direction between successive tooth passes, strictly positive.

teeth

Integer number of active teeth used in the feed relation, at least 1.

Strictly positive spindle speed, converted to rad/s for calculation.

Initial values are examples.

Results

Feed speed vf
0.2m/min

Substitution in SI units

vf=(5×10-5 m)×4×(104.7 rads)2×acos(−1)=0.2 m/min

Nominal distribution of feed between teeth; runout and chip thinning are not corrected, and a non-integer calculated tooth count remains theoretical.

Linear feed per tooth

Translation between two tooth passesvf = 0.2 m/minPass 1Next passfz = 0.05 mm
z=4 active teethω=1,000 rpm
Projection of two successive positions along the feed direction.A calculated non-integer tooth count remains theoretical.Not to scale

Estimated reading time : 7 min · 1266 words

Calculation details

The steps below use the inputs and units selected in the calculator.

01 · Feed rate

FORMULA

vᶠ=fz×z×ω2×acos(−1)

NUMERICAL SUBSTITUTION

vᶠ=(0.05 mm)×4×(1,000 rpm)2×acos(−1)

RESULT

vᶠ=0.2 m/min

Table feed, feed per tooth and spindle speed

The chip load fz is the tool feed per tooth in the kinematic relation; it does not always coincide with the maximum chip thickness.

Formulas and symbols

Choose the unknown, then enter the other three quantities. fz is feed per tooth and z is the number of active teeth as defined by the manufacturer, not the number in contact at any given instant.

vᶠ=fz×z×ω2×acos(−1)Linear table feed for the entered speed, number of teeth and feed per tooth.

fz=vᶠ×2×acos(−1)z×ωNominal feed between tooth passes, distinct from the actual chip thickness.

ω=vᶠ×2×acos(−1)fz×zSpeed compatible with the specified table feed and feed per tooth; no machine limits are checked.

z=vᶠ×2×acos(−1)fz×ωTheoretical number of teeth. If it is not an integer, choose an actual tool and then recalculate the other parameters.

  • fz: nominal feed per tooth, mm per tooth with the default length unit.
  • z: number of active teeth; in inverse mode, theoretical number of teeth, dimensionless.
  • ω: spindle speed, tr/min by default.
  • vᶠ: linear feed rate, m/min by default.

Guidance for interpreting results

Quantity or conditionInterpretation
Feed per toothNominal distance advanced between tooth passes
Feed per revolutionFeed per tooth multiplied by the number of teeth
Non-integer theoretical number of teethAdjust a parameter or choose an actual tool, then recalculate
Spindle speed conversionω [rad/s] = 2π×n [rpm]/60
Length conversion1 m=1 000 mm
Feed ratevᶠ=fz×z×n: linear table feed, in mm/min or m/min
Spindle speedNumber of revolutions per minute, derived from cutting speed and tool diameter
Feed per tooth too lowThe tooth rubs instead of cutting: heating and rapid cutting-edge wear
Feed per tooth too highHigh cutting force, risk of chipping or tool breakage

Sandvik Coromant — Milling Formulas and Definitions ; NIST — SI prefixes.

Chip thinning as a function of radial engagement

Radial engagement ae / DMaximum chip thickness (cylindrical cutter, straight teeth)
0.50 (half the diameter or more)1.00×fz: chip thickness reaches the feed per tooth
0.250.87×fz
0.100.60×fz
0.050.44×fz
Geometric relation (ae ≤ D/2)hmax = fz×2 √[(ae/D) × (1 − ae/D)]

Harvey Performance Company - How to Combat Chip Thinning.

Choose fz from the tool manufacturer's data

IdentifyCheck
Tool and diameterUse the exact tool reference; there is no universal range for a material.
Material and conditionCheck alloy, hardness and treatment against the manufacturer's data.
Radial engagement ae/DLow radial engagement can reduce chip thickness; use the manufacturer's correction.
Depth aₚ and setupCheck usable length, overhang and rigidity.
Theoretical tooth count zSelect an available tool with an integer tooth count, then recalculate feed.
Machine limitsCheck maximum spindle speed, available feed and tool conditions.

Sandvik Coromant — Milling Formulas and Definitions ; Harvey Performance Company - How to Combat Chip Thinning.

Worked examples

Example 1: 0,05 mm per tooth, four teeth and 1 000 tr/min

The feed rate is 200 mm/min.

Example 2: 200 mm/min, four teeth and 1 000 tr/min

The nominal feed is 0,05 mm per tooth.

Example 3: 200 mm/min and four teeth at 0,05 mm per tooth

The required spindle speed is 1 000 tr/min.

Example 4: 200 mm/min, 0,05 mm per tooth and 1 000 tr/min

The theoretical number of active teeth is 4.

Example 5: 10 mm cutter with four teeth, 1 mm radial engagement, 3 000 rpm

With ae/D=1/10, the maximum chip thickness is 0.6×fz (see the chip thinning table). To target a thickness of 0.06 mm, use fz=0.06/0.6=0.10 mm per tooth. The calculator then gives vᶠ=0.10×4×3 000=1 200 mm/min, or 1.2 m/min, instead of 0.72 m/min with the uncorrected fz=0.06 mm.

Example 6: Table feed limited to 2 m/min, two-tooth cutter, 0.04 mm per tooth

In this exercise, the machine limits the spindle to 12 000 rpm. To preserve the selected feed per tooth, the table feed is reduced; increasing the tooth load would require a compatible recommendation from the manufacturer.

With fz=0.04 mm/tooth and z=2, reaching 2 000 mm/min would require n=2 000/(0.04×2)=25 000 rpm. At 12 000 rpm, vᶠ=0.04×2×12 000=960 mm/min.

Assumptions and limitations

Milling at constant feed, with a known number of active teeth. Feed per tooth is nominal; no correction for chip thinning, runout or stability. A calculated non-integer number of teeth is neither rounded nor treated as an available tool.

The chip-thinning table describes simplified peripheral milling geometry; its correction is not applied automatically. aₑ and aₚ are not inputs to this kinematic calculation.

Common mistakes

Entering mm/tr instead of mm/dent; counting an inactive tooth as cutting; specifying a non-integer number of teeth.

Frequently asked questions

Is feed per tooth the actual chip thickness?

Not necessarily. The thickness depends on engagement and geometry; chip thinning is not corrected here.

Which teeth should be counted?

The number of active tool teeth as defined by the manufacturer. Do not confuse this with the number in contact at any given instant.

What if the calculated tooth count is fractional?

The result describes a theoretical combination, not a cutter with part of a tooth. Choose an available tooth count and recalculate table feed or feed per tooth. Rounding the count while keeping every other setting changes the intended relationship.

How should a spindle limit be handled?

Choose a speed compatible with the machine and tool, then recalculate table feed using the chosen tooth count and nominal feed per tooth. Automatically increasing chip load to maintain productivity may exceed the tool manufacturer’s recommendation.

How do you convert cutting speed to spindle speed?

Use n=1 000 × vc / (π×D), with vc in m/min, D in mm and n in rpm. For vc = 120 m/min and a diameter of 10 mm, the result is about 3 820 rpm. First calculate this speed with the rotational speed calculator, then enter it here.

What should you do if the calculated number of teeth is not an integer?

A result such as 3.6 means that the other three inputs do not correspond to a real tool. Choose a cutter with 3 or 4 teeth, then recalculate the feed per tooth or feed rate using that whole number to obtain consistent parameters.

What feed per tooth should you choose if you do not know the recommended value?

Use the manufacturer's recommendations for the material, diameter, engagement and cutting grade concerned. Without this information, this calculator can check a kinematic relationship, but it does not determine a suitable tooth load or a safe setup procedure.

Does feed rate depend on tool diameter?

Not directly: the relation vᶠ=fz×z×n contains no diameter. Diameter has an indirect effect because it determines the spindle speed for a given cutting speed, the available number of teeth and the permissible feed per tooth.