Machining and manufacturing
Milling feed: calculate table feed and feed per tooth
Relate table feed, feed per tooth, spindle speed and the number of active teeth of a milling cutter. Choose the quantity to find; the calculated number of teeth remains a theoretical value to compare with an actual tool.
Milling feed and chip load per tooth
Linear displacement in the feed direction between successive tooth passes, strictly positive.
Integer number of active teeth used in the feed relation, at least 1.
Strictly positive spindle speed, converted to rad/s for calculation.
Initial values are examples.
Results
Substitution in SI units
Nominal distribution of feed between teeth; runout and chip thinning are not corrected, and a non-integer calculated tooth count remains theoretical.
Linear feed per tooth
Estimated reading time : 7 min · 1266 words
Calculation details
The steps below use the inputs and units selected in the calculator.
Table feed, feed per tooth and spindle speed
The chip load fz is the tool feed per tooth in the kinematic relation; it does not always coincide with the maximum chip thickness.
Formulas and symbols
Choose the unknown, then enter the other three quantities. fz is feed per tooth and z is the number of active teeth as defined by the manufacturer, not the number in contact at any given instant.
Linear table feed for the entered speed, number of teeth and feed per tooth.
Nominal feed between tooth passes, distinct from the actual chip thickness.
Speed compatible with the specified table feed and feed per tooth; no machine limits are checked.
Theoretical number of teeth. If it is not an integer, choose an actual tool and then recalculate the other parameters.
- fz: nominal feed per tooth, mm per tooth with the default length unit.
- z: number of active teeth; in inverse mode, theoretical number of teeth, dimensionless.
- ω: spindle speed, tr/min by default.
- vᶠ: linear feed rate, by default.
Guidance for interpreting results
| Quantity or condition | Interpretation |
|---|---|
| Feed per tooth | Nominal distance advanced between tooth passes |
| Feed per revolution | Feed per tooth multiplied by the number of teeth |
| Non-integer theoretical number of teeth | Adjust a parameter or choose an actual tool, then recalculate |
| Spindle speed conversion | ω [] = 2 [rpm]/60 |
| Length conversion | |
| Feed rate | : linear table feed, in or |
| Spindle speed | Number of revolutions per minute, derived from cutting speed and tool diameter |
| Feed per tooth too low | The tooth rubs instead of cutting: heating and rapid cutting-edge wear |
| Feed per tooth too high | High cutting force, risk of chipping or tool breakage |
Sandvik Coromant — Milling Formulas and Definitions ; NIST — SI prefixes.
Chip thinning as a function of radial engagement
| Radial engagement ae / D | Maximum chip thickness (cylindrical cutter, straight teeth) |
|---|---|
| 0.50 (half the diameter or more) | : chip thickness reaches the feed per tooth |
| 0.25 | |
| 0.10 | |
| 0.05 | |
| Geometric relation (ae ≤ ) | hmax = √[(ae/D) × (1 − ae/D)] |
Choose fz from the tool manufacturer's data
| Identify | Check |
|---|---|
| Tool and diameter | Use the exact tool reference; there is no universal range for a material. |
| Material and condition | Check alloy, hardness and treatment against the manufacturer's data. |
| Radial engagement | Low radial engagement can reduce chip thickness; use the manufacturer's correction. |
| Depth aₚ and setup | Check usable length, overhang and rigidity. |
| Theoretical tooth count z | Select an available tool with an integer tooth count, then recalculate feed. |
| Machine limits | Check maximum spindle speed, available feed and tool conditions. |
Sandvik Coromant — Milling Formulas and Definitions ; Harvey Performance Company - How to Combat Chip Thinning.
Worked examples
Example 1: 0,05 mm per tooth, four teeth and 1 000 tr/min
The feed rate is .
Example 2: , four teeth and 1 000 tr/min
The nominal feed is 0,05 mm per tooth.
Example 3: and four teeth at 0,05 mm per tooth
The required spindle speed is 1 000 tr/min.
Example 4: , 0,05 mm per tooth and 1 000 tr/min
The theoretical number of active teeth is 4.
Example 5: 10 mm cutter with four teeth, 1 mm radial engagement, 3 000 rpm
With ae/, the maximum chip thickness is (see the chip thinning table). To target a thickness of 0.06 mm, use per tooth. The calculator then gives , or , instead of with the uncorrected .
Example 6: Table feed limited to , two-tooth cutter, 0.04 mm per tooth
In this exercise, the machine limits the spindle to 12 000 rpm. To preserve the selected feed per tooth, the table feed is reduced; increasing the tooth load would require a compatible recommendation from the manufacturer.
With /tooth and , reaching would require . At 12 000 rpm, .
Assumptions and limitations
Milling at constant feed, with a known number of active teeth. Feed per tooth is nominal; no correction for chip thinning, runout or stability. A calculated non-integer number of teeth is neither rounded nor treated as an available tool.
The chip-thinning table describes simplified peripheral milling geometry; its correction is not applied automatically. aₑ and aₚ are not inputs to this kinematic calculation.
Common mistakes
Entering mm/tr instead of mm/dent; counting an inactive tooth as cutting; specifying a non-integer number of teeth.
Frequently asked questions
Is feed per tooth the actual chip thickness?
Not necessarily. The thickness depends on engagement and geometry; chip thinning is not corrected here.
Which teeth should be counted?
The number of active tool teeth as defined by the manufacturer. Do not confuse this with the number in contact at any given instant.
What if the calculated tooth count is fractional?
The result describes a theoretical combination, not a cutter with part of a tooth. Choose an available tooth count and recalculate table feed or feed per tooth. Rounding the count while keeping every other setting changes the intended relationship.
How should a spindle limit be handled?
Choose a speed compatible with the machine and tool, then recalculate table feed using the chosen tooth count and nominal feed per tooth. Automatically increasing chip load to maintain productivity may exceed the tool manufacturer’s recommendation.
How do you convert cutting speed to spindle speed?
Use × vc / , with vc in , D in mm and n in rpm. For vc = and a diameter of 10 mm, the result is about 3 820 rpm. First calculate this speed with the rotational speed calculator, then enter it here.
What should you do if the calculated number of teeth is not an integer?
A result such as 3.6 means that the other three inputs do not correspond to a real tool. Choose a cutter with 3 or 4 teeth, then recalculate the feed per tooth or feed rate using that whole number to obtain consistent parameters.
What feed per tooth should you choose if you do not know the recommended value?
Use the manufacturer's recommendations for the material, diameter, engagement and cutting grade concerned. Without this information, this calculator can check a kinematic relationship, but it does not determine a suitable tooth load or a safe setup procedure.
Does feed rate depend on tool diameter?
Not directly: the relation contains no diameter. Diameter has an indirect effect because it determines the spindle speed for a given cutting speed, the available number of teeth and the permissible feed per tooth.