Machining and manufacturing
Tap drill: diameter calculation and M1 to M48 table
Choose thread , compare the referenced usual drill with D − p and the theoretical diameter for a requested thread percentage, or estimate the percentage for the selected drill. The 114 coarse and fine pitch references remain in the tables. These calculations apply only to cutting taps.
Drilling before metric tapping
Nominal thread diameter, greater than the pitch.
Axial distance between consecutive thread crests, strictly positive.
Theoretical percentage strictly positive and no greater than 100%; 75% is an example.
Drill diameter to compare with the thread and calculated theoretical percentage.
Shortcuts :
Thread references (114 sizes)
Selecting a thread keeps your drill diameter; shortcuts and “Use this drill” apply the referenced value.
Estimated percentage for this usual drill : 73.9 %
The manufacturer reference does not set a universal thread percentage. Check the actual hole diameter and cutting conditions.
Initial values are examples.
Results
Model convention for cutting taps: E and Eest are the numerical percentage values, for example 75 for 75%, with all three lengths in the same unit.
The coefficient 76.98 is taken from the relation in Gühring — Tap Drill Sizes, p. 2; this percentage is neither a measurement of the produced thread nor a strength check.
Cutting taps only; choose the drill according to the tool data sheet and check the actual hole diameter.
Applied formulas
Values are substituted in SI units and results are shown in the selected units.
Estimated reading time : 14 min · 2609 words
Calculation details
The usual drill comes from a manufacturer table; D − p is a separate approximation. The Gühring relation and its inverse estimate a theoretical percentage for cutting taps.
02 · Theoretical diameter at requested percentage
03 · Estimated thread percentage for selected drill (%)
Tap drill, nominal diameter and thread pitch
The nominal diameter D designates the thread, while pitch p is the axial distance between two consecutive thread crests. In M8 × 1,25, D is 8 mm and p is 1,25 mm. The tap drill leaves the material needed for cutting the threads with a cutting tap. It is neither a screw clearance hole nor the theoretical minor diameter of the thread.
Formulas and symbols
E and Eest are numerical percentages (75 means 75%). All lengths use the same unit. The factor 76.98 applies to 60° metric cutting taps.
(approximation, separate from the referenced usual drill)
(Gühring: cutting taps, E expressed as a percentage)
(inverse of the same model; an estimate, not a measurement or strength check)
- D: nominal thread diameter.
- p: thread pitch.
- d: selected drill diameter.
- dth: theoretical diameter at requested percentage E.
- Eest: estimated theoretical percentage for the selected drill, in %.
- D − p: approximation independent of the manufacturer table.
Cutting taps: coarse pitch M1–M48 — Thürmer series
The 34 diameter × pitch pairs of the Thürmer coarse-pitch series between M1 and M48 are shown. Select the row matching BOTH the thread diameter and pitch; the published drill diameter applies to cutting taps.
| Thread | Pitch (mm) | Calculated D − p (mm) | Thürmer: cutting tap drill (mm) |
|---|---|---|---|
| M1 × 0,25 | 0,25 | 0,75 | 0,75 |
| M1,2 × 0,25 | 0,25 | 0,95 | 0,95 |
| M1,4 × 0,3 | 0,3 | 1,1 | 1,1 |
| M1,6 × 0,35 | 0,35 | 1,25 | 1,25 |
| M1,8 × 0,35 | 0,35 | 1,45 | 1,45 |
| M2 × 0,4 | 0,4 | 1,6 | 1,6 |
| M2,2 × 0,45 | 0,45 | 1,75 | 1,75 |
| M2,5 × 0,45 | 0,45 | 2,05 | 2,05 |
| M3 × 0,5 | 0,5 | 2,5 | 2,5 |
| M3,5 × 0,6 | 0,6 | 2,9 | 2,9 |
| M4 × 0,7 | 0,7 | 3,3 | 3,3 |
| M4,5 × 0,75 | 0,75 | 3,75 | 3,75 |
| M5 × 0,8 | 0,8 | 4,2 | 4,2 |
| M6 × 1 | 1 | 5 | 5 |
| M7 × 1 | 1 | 6 | 6 |
| M8 × 1,25 | 1,25 | 6,75 | 6,8 |
| M9 × 1,25 | 1,25 | 7,75 | 7,8 |
| M10 × 1,5 | 1,5 | 8,5 | 8,5 |
| M11 × 1,5 | 1,5 | 9,5 | 9,5 |
| M12 × 1,75 | 1,75 | 10,25 | 10,25 |
| M14 × 2 | 2 | 12 | 12 |
| M16 × 2 | 2 | 14 | 14 |
| M18 × 2,5 | 2,5 | 15,5 | 15,5 |
| M20 × 2,5 | 2,5 | 17,5 | 17,5 |
| M22 × 2,5 | 2,5 | 19,5 | 19,5 |
| M24 × 3 | 3 | 21 | 21 |
| M27 × 3 | 3 | 24 | 24 |
| M30 × 3,5 | 3,5 | 26,5 | 26,5 |
| M33 × 3,5 | 3,5 | 29,5 | 29,5 |
| M36 × 4 | 4 | 32 | 32 |
| M39 × 4 | 4 | 35 | 35 |
| M42 × 4,5 | 4,5 | 37,5 | 37,5 |
| M45 × 4,5 | 4,5 | 40,5 | 40,5 |
| M48 × 5 | 5 | 43 | 43 |
Source for every row: Thürmer Tools, “ISO metric coarse 60°” table, “Drill, cut” column. The series published between M1 and M48 comprises the 34 pairs above; it does not include every possible intermediate diameter. The D − p column is calculated separately: M8 × 1,25 gives 6,75 mm, while Thürmer specifies 6,8 mm. Values depend on the manufacturer reference: for M12 × 1,75, the Thürmer table gives 10,25 mm versus 10,20 mm from BAER; for M4,5 × 0,75, the respective values are 3,75 and 3,70 mm. These variants are not automatic rounding by the calculator. Thürmer presents its table for approximately 75 % thread engagement, to be checked against the drawing and required tolerance. Thürmer Tools — coarse pitch M1–M48: Drill, cut column; values distinct from forming ; BAER — tap drill sizes for cutting taps, ISO DIN 13 metric fine series and coarse-pitch variants.
Cutting taps: fine pitches M3–M12 — BAER selection
This M3–M12 section contains 21 diameter × fine-pitch pairs published by BAER for cutting taps. Pitch must be specified: one nominal size has multiple rows. The columns separate the calculated estimate from the source drill size.
| Thread | Pitch (mm) | Calculated D − p (mm) | BAER: cutting tap drill (mm) |
|---|---|---|---|
| M3 × 0,35 | 0,35 | 2,65 | 2,65 |
| M3,5 × 0,35 | 0,35 | 3,15 | 3,15 |
| M4 × 0,35 | 0,35 | 3,65 | 3,65 |
| M4 × 0,5 | 0,5 | 3,5 | 3,5 |
| M5 × 0,5 | 0,5 | 4,5 | 4,5 |
| M6 × 0,5 | 0,5 | 5,5 | 5,5 |
| M6 × 0,75 | 0,75 | 5,25 | 5,2 |
| M7 × 0,75 | 0,75 | 6,25 | 6,2 |
| M8 × 0,5 | 0,5 | 7,5 | 7,5 |
| M8 × 0,75 | 0,75 | 7,25 | 7,2 |
| M8 × 1 | 1 | 7 | 7 |
| M9 × 1 | 1 | 8 | 8 |
| M10 × 0,5 | 0,5 | 9,5 | 9,5 |
| M10 × 0,75 | 0,75 | 9,25 | 9,2 |
| M10 × 1 | 1 | 9 | 9 |
| M10 × 1,25 | 1,25 | 8,75 | 8,8 |
| M11 × 1 | 1 | 10 | 10 |
| M12 × 0,75 | 0,75 | 11,25 | Not adopted — sources disagree |
| M12 × 1 | 1 | 11 | 11 |
| M12 × 1,25 | 1,25 | 10,75 | 10,8 |
| M12 × 1,5 | 1,5 | 10,5 | 10,5 |
Source for every row: BAER, “MF - Metric fine thread ISO DIN 13” section, for cutting taps only. The selection includes the 80 published diameter × pitch pairs from M3 to M48, without claiming to cover every possible metric pitch. 79 drill diameters are transcribed; no value is selected for M12 × 0,75: BAER gives 10,20 mm and Nachreiner 11,20 mm. Resolve this discrepancy using the tool data sheet; 11,25 mm is only D − p. For M4 × 0,35, BAER and Nachreiner give 3,65 mm: the conflicting 3,5 mm value in the Thürmer FAQ is not used. No manufacturer cell has been filled with D − p. The BAER table does not specify a single material or thread engagement percentage for these rows. BAER — tap drill sizes for cutting taps, ISO DIN 13 metric fine series and coarse-pitch variants ; Nachreiner — Core Hole Table: checking discrepancies for M4 × 0,35 and M12 × 0,75 ; Thürmer Tools — coarse pitch M1–M48: Drill, cut column; values distinct from forming.
Cutting taps: fine pitches M13–M24 — BAER selection
This M13–M24 section contains 23 diameter × fine-pitch pairs published by BAER for cutting taps. Pitch must be specified: one nominal size has multiple rows. The columns separate the calculated estimate from the source drill size.
| Thread | Pitch (mm) | Calculated D − p (mm) | BAER: cutting tap drill (mm) |
|---|---|---|---|
| M13 × 1 | 1 | 12 | 12 |
| M13 × 1,5 | 1,5 | 11,5 | 11,5 |
| M13 × 1,75 | 1,75 | 11,25 | 11,2 |
| M14 × 1 | 1 | 13 | 13 |
| M14 × 1,25 | 1,25 | 12,75 | 12,8 |
| M14 × 1,5 | 1,5 | 12,5 | 12,5 |
| M15 × 1 | 1 | 14 | 14 |
| M15 × 1,5 | 1,5 | 13,5 | 13,5 |
| M15 × 2 | 2 | 13 | 13 |
| M16 × 1 | 1 | 15 | 15 |
| M16 × 1,5 | 1,5 | 14,5 | 14,5 |
| M18 × 1 | 1 | 17 | 17 |
| M18 × 1,5 | 1,5 | 16,5 | 16,5 |
| M18 × 2 | 2 | 16 | 16 |
| M20 × 1 | 1 | 19 | 19 |
| M20 × 1,5 | 1,5 | 18,5 | 18,5 |
| M20 × 2 | 2 | 18 | 18 |
| M22 × 1 | 1 | 21 | 21 |
| M22 × 1,5 | 1,5 | 20,5 | 20,5 |
| M22 × 2 | 2 | 20 | 20 |
| M24 × 1 | 1 | 23 | 23 |
| M24 × 1,5 | 1,5 | 22,5 | 22,5 |
| M24 × 2 | 2 | 22 | 22 |
Source for every row: BAER, “MF - Metric fine thread ISO DIN 13” section, cutting taps. This M13–M24 section includes every pair published by BAER in that interval. The full selection on this page runs from M3 to M48; it does not cover every possible pitch. The drill values are transcribed, while D − p is calculated separately. BAER does not specify a single material or thread engagement for these rows; check the tap data sheet and required tolerance. No values apply to forming. BAER — tap drill sizes for cutting taps, ISO DIN 13 metric fine series and coarse-pitch variants.
Cutting taps: fine pitches M25–M48 — BAER selection
This M25–M48 section contains 36 diameter × fine-pitch pairs published by BAER for cutting taps. Pitch must be specified: one nominal size has multiple rows. The columns separate the calculated estimate from the source drill size.
| Thread | Pitch (mm) | Calculated D − p (mm) | BAER: cutting tap drill (mm) |
|---|---|---|---|
| M25 × 1 | 1 | 24 | 24 |
| M25 × 1,5 | 1,5 | 23,5 | 23,5 |
| M26 × 1 | 1 | 25 | 25 |
| M26 × 1,5 | 1,5 | 24,5 | 24,5 |
| M27 × 1 | 1 | 26 | 26 |
| M27 × 1,5 | 1,5 | 25,5 | 25,5 |
| M27 × 2 | 2 | 25 | 25 |
| M28 × 1,5 | 1,5 | 26,5 | 26,5 |
| M28 × 2 | 2 | 26 | 26 |
| M30 × 1 | 1 | 29 | 29 |
| M30 × 1,5 | 1,5 | 28,5 | 28,5 |
| M30 × 2 | 2 | 28 | 28 |
| M32 × 1,5 | 1,5 | 30,5 | 30,5 |
| M33 × 1,5 | 1,5 | 31,5 | 31,5 |
| M33 × 2 | 2 | 31 | 31 |
| M34 × 1,5 | 1,5 | 32,5 | 32,5 |
| M35 × 1,5 | 1,5 | 33,5 | 33,5 |
| M36 × 1,5 | 1,5 | 34,5 | 34,5 |
| M36 × 2 | 2 | 34 | 34 |
| M36 × 3 | 3 | 33 | 33 |
| M38 × 1,5 | 1,5 | 36,5 | 36,5 |
| M39 × 1,5 | 1,5 | 37,5 | 37,5 |
| M39 × 2 | 2 | 37 | 37 |
| M39 × 3 | 3 | 36 | 36 |
| M40 × 1,5 | 1,5 | 38,5 | 38,5 |
| M40 × 2 | 2 | 38 | 38 |
| M40 × 3 | 3 | 37 | 37 |
| M42 × 1,5 | 1,5 | 40,5 | 40,5 |
| M42 × 2 | 2 | 40 | 40 |
| M42 × 3 | 3 | 39 | 39 |
| M45 × 1,5 | 1,5 | 43,5 | 43,5 |
| M45 × 2 | 2 | 43 | 43 |
| M45 × 3 | 3 | 42 | 42 |
| M48 × 1,5 | 1,5 | 46,5 | 46,5 |
| M48 × 2 | 2 | 46 | 46 |
| M48 × 3 | 3 | 45 | 45 |
Source for every row: BAER, “MF - Metric fine thread ISO DIN 13” section, cutting taps. This M25–M48 section includes every pair published by BAER in that interval. The full selection on this page runs from M3 to M48; it does not cover every possible pitch. The drill values are transcribed, while D − p is calculated separately. BAER does not specify a single material or thread engagement for these rows; check the tap data sheet and required tolerance. No values apply to forming. BAER — tap drill sizes for cutting taps, ISO DIN 13 metric fine series and coarse-pitch variants.
Worked examples
Example 1: Preparing an M6 × 1 tapped hole
For and , the estimate gives 5 mm. The manufacturer's table also specifies a 5 mm tap drill for a cutting tap.
Example 2: Understanding the difference for M8 × 1,25
For M8 × 1.25 the usual Thürmer drill is 6.8 mm; D − p is 6.75 mm. The Gühring model estimates 73.9008% for a 6.8 mm drill (74% in its rounded table), not a universal 75%. A requested 75% gives a theoretical diameter of 6.7822 mm, distinct from the available drill.
Example 3: M10 with a 1 mm fine pitch
The pitch distinguishes this thread from other M10 threads. This exercise computes only the theoretical difference; the final drill choice depends on the cutting tap and machining conditions.
; : .
Example 4: Estimate the percentage for M48 × 3 with a 45 mm drill
%. Select the thread before the drill: a 6.4 mm drill for this thread exceeds 100% in this model and is rejected as incompatible.
Assumptions and limitations
This relationship applies only to cutting taps for 60° metric threads. The tables are manufacturer references for the displayed diameter × pitch pairs, not instructions valid for every material or tap. Confirm the tool, tolerance class, material, target thread engagement and diameter actually obtained. Forming taps displace material and require their own tap drill table; no forming values are given here. The calculation determines neither drilling depth, lubrication nor the tap type suitable for a blind or through hole. Outside the two displayed series, entering D and p produces only an estimate and does not create a manufacturer recommendation.
The calculated percentage is a geometric estimate, not a measured actual percentage or a strength or tolerance check. The domain % only checks geometric compatibility; it does not recommend every percentage in that range. Runout can enlarge the hole and reduce actual thread percentage. Gühring uses a different relation for forming taps; it is not used here.
Common mistakes
Do not enter threads per inch in place of metric pitch. Do not assume that an M diameter always has a single pitch: M10 × 1 and M10 × 1,5 differ. Distinguish screw diameter, clearance hole and tapped pilot hole. Do not always round down or apply D − p to a forming tap.
Frequently asked questions
Is the result directly a drilling instruction?
It is an estimate. Choose the drill bit recommended for the tap and check the diameter obtained in the actual material.
Why exclude forming taps?
They displace material without removing chips in the same way. Their pilot hole is generally larger and depends strongly on the material and the required thread engagement.
What drill diameter for an M4 thread?
For M4 × 0,7 with a cutting tap, the Thürmer table specifies a 3,3 mm drill bit. The estimate also gives . Check the pitch: an M4 with a different pitch requires a different tap drill.
Which drill bit for M5 and M10?
For the pitches in the table, M5 × 0,8 corresponds to 4,2 mm and M10 × 1,5 to 8,5 mm. These values apply to cutting taps. Nominal diameter alone is insufficient: always specify the pitch and check the manufacturer’s recommendations.
Does fine pitch change the drill diameter?
Yes. At a constant nominal diameter, a smaller pitch gives a larger theoretical tap drill. For M10 × 1,5, D − p is 8,5 mm and Thürmer also specifies 8,5 mm; for M10 × 1, D − p is 9 mm and BAER specifies 9 mm. Consult the row for the exact pitch, then the recommendation from your tap manufacturer.
Why does M8 give 6,75 mm while the table specifies 6,8 mm?
For M8 × 1.25 the usual Thürmer drill is 6.8 mm; D − p is 6.75 mm. The Gühring model estimates 73.9008% for a 6.8 mm drill (74% in its rounded table), not a universal 75%. A requested 75% gives a theoretical diameter of 6.7822 mm, distinct from the available drill.